• Boundary conditions are extremely important. Indeed, they cause the most common errors.
• OpenFOAM uses similar set-up as other solvers.
• At the inlet (flow inlet) to the computational domain total pressure and total temperature are set. The rest of variables is reconstructed.
• At the outlet the static pressure is set.
• At the rigid walls velocity is set to zero.
• Multiple Reference Frame (MRF) is used for rotational components.
• For steady-state computations the initial conditions have no influence to the results.
• For steady-state computations the initial conditions just help to make the case run.

The main variables to be set are following:

• static pressure p
• velocity vector U
• static temperature T
• turbulent kinetic energy k
• specific turbulence dissipation omega

The initial and boundary conditions for all variables are set in files located in directories called by numbers. Typically directory 0 is recommended to start simulation from. Initial conditions are set in parameter internalField putting the values into the cell centers. At boundaries, initial conditions are set individually by parameter value.

Following table shows recommended model boundary conditions for computed variables:

The shortcuts from the above table have following meaning:

• tP – totalPressure, constant e.g. 150 000 Pa, gamma = 1.4 [-] is specific heat ratio

   

• pDIV – pressureDirectedInletVelocity, velocity is computed from difference between total and static pressure, inletDirection is velocity vector to be specified

   

• tT – totalTemperature, constant e.g. 293 K, gamma = 1.4 [-] is specific heat ratio

   

• tIKEI – turbulentIntensityKineticEnergyInlet, intensity = 0.02, corresponds to turbulence intensity 2%

   

• fV – fixedValue, e.g. velocity at the wall (0 0 0), or omega at inlet

   

• fMV – fixedMeanValue, is the same as fixed value e.g. for pressure, but certain freedom is allowed to keep the variable average equal to meanValue

   

• zG – zeroGradient, the flux of the variable is zero in direction perpendicular to the surface

   

• TWF – compressible::turbulentTemperatureCoupledBaffleMixed special boundary condition for temperature enabling heat transfer from/to other regions

   

• kWF – compressible::kqRWallFunction is standard wall function for k for compressible flow

   

• oWF – compressible::omegaWallFunction is standard wall function for omega for compressible flow

   

• mPV – mixingPlaneVelocity, averaged velocity is mapped from neighbour patch

   

• mP – mixingPlane, averaged variable is mapped from neighbour patch

   

• iO – inletOutlet is by default zeroGradient, but change to fixedValue when velocity vector direction aims inside the computational domain (backward flow)

   

• cc – calculated, boundary values of a certain quantity is simply calculated, in accordance with its definiton, from values of other quantities that already have prescribed their boundary conditions

There is an example of a field that we use due to formal reasons only – pressure field inside the solid region. For this field we prescribe boundary conditions of type calculated.

Two other variables must be presented for postprocessing purposes: total pressure pTot and total temperature TTot. The boundary conditions for total pressure and total temperature are formal and are always the same:

boundaryField
{
    "(.*)"
    {
        type zeroGradient;
    }
}