1
2
6
5
4
3

Previous: Computation set-up Up: Computation set-up Next: Turbulent quantities

This is an automatically generated documentation by LaTeX2HTML utility. In case of any issue, please, contact us at info@cfdsupport.com.

Initial and boundary conditions for p and u​

  • Initial and boundary conditions are usually stored in directory /0.
  • Solver simpleFoam requires pressure p, velocity U and turbulence quantities initial and boundary conditions.
  • Number named directories represent time layouts of solution.

     

  • Configure file for pressure:
    # cat $FOAM_RUN /pitzDaily/0/p

     

    dimensions      [0 2 -2 0 0 0 0];

internalField   uniform 0;

boundaryField
{
    inlet
    {
        type            zeroGradient;
    }

    outlet
    {
        type            fixedValue;
        value           uniform 0;
    }

    upperWall
    {
        type            zeroGradient;
    }

    lowerWall
    {
        type            zeroGradient;
    }

    frontAndBack
    {
        type            empty;
    }
}
  • Physical dimensions of pressure: $ m^{2}s^{-2}$ (kinematic pressure) is in OpenFOAM written as: [0 2 -2 0 0 0 0]
  • Initial condition: $ p_0 = 0$ (constant in whole flow domain)
  • Standard boundary conditions for incompressible fluid flow in a channel are following:
    • $ p_{\infty} = 0$ at the outlet of the domain
    • Pressure is extrapolated at the walls and at the inlet
    • At boundary frontAndBack (front side and back side) we set boundary condition empty, flow is not solved in this direction (quasi 3D – 2D simulation)

     

  • Configuration file for velocity:
    # cat $FOAM_RUN /pitzDaily/0/U

     

    dimensions      [0 1 -1 0 0 0 0];

internalField   uniform (0 0 0);

boundaryField
{
    inlet
    {
        type            fixedValue;
        value           uniform (10 0 0);
    }

    outlet
    {
        type            zeroGradient;
    }

    upperWall
    {
        type            noSlip;
    }

    lowerWall
    {
        type            noSlip;
    }

    frontAndBack
    {
        type            empty;
    }
}
  • Physical dimensions of velocity: [0 1 -1 0 0 0 0] $ \rightarrow$ $ m/s$
  • Initial condition: $ U_0 = (10, 0, 0)$ (constant in whole domain)
  • Standard boundary conditions for incompressible fluid flow in a channel:
    • $ U_{\infty} = (10, 0, 0)$ at the inlet
    • Velocity is extrapolated at the outlet
    • Velocity is zero at the walls
    • At boundary frontAndBack (front side and back side) is boundary condition empty, flow is not solved in this direction (quasi 3D – 2D simulation)
  •  
1
2
6
5
4
3

Previous: Computation set-up Up: Computation set-up Next: Turbulent quantities

OpenFOAM Training by CFD Support,   CFD SUPPORT,   info@cfdsupport.com    +420 212 243 883      © CFD support, s.r.o., Sokolovská 270/201, 190 00 Praha 9, Czech Republic

1
2
6
5
4
3

Previous: Stator Efficiency Up: Formulas for the Efficiency Next: TCFD Solvers
This is an automatically generated documentation by LaTeX2HTML utility. In case of any issue, please, contact us at info@cfdsupport.com.

Virtual Tunnel Efficiency

The simulation type virutalTunnel has no efficiency formula to be evaluated. This simulation type is primarily focused on forces and force coefficient evaluation.

OpenFOAM Training by CFD Support,   CFD SUPPORT,   info@cfdsupport.com    +420 212 243 883      © CFD support, s.r.o., Sokolovská 270/201, 190 00 Praha 9, Czech Republic